You can use model tree filters to control both item and feature type display.
Figure 4 – Model Tree Used Sketches Before and After
The model tree contains a hierarchical list of features or components in the order created. You can filter what is displayed in the model tree both in terms of item display and feature types. The filtering of item display and feature types is controlled by the Model Tree Items dialog box, shown in Figure 1.
Open the Model Tree Items dialog box by clicking Settings of the model tree, and then selecting Tree Filters.
The filters applied to the model tree are unique to each window except in the case of assemblies, where applied filters only propagate to sub-assemblies of assemblies.
Controlling Model Tree Item Display
The display of the following specific types of items is controlled on the left side of the Model Tree Items dialog box:
• Features – Figure 2 shows the model tree with the display of features turned on and off. Notice that when features are turned off, they are turned off in both the assembly and part levels of the model tree. When features are turned off in the assembly, you can only see the components that are assembled, but nothing more granular. By default, features are turned on for parts and turned off for assemblies.
• Placement folder – Toggles the display of component placement constraints within assembly components.
• Annotations – Toggles the display of annotations.
• Sections – Toggles the display of cross-sections.
• Suppressed Objects – Toggles the display of suppressed features and components. Suppressed objects in the model tree are preceded with a
black square. In Figure 3, the EDGE_ROUNDS and LUBE_HOLE features are suppressed. If the display of suppressed objects was turned off, these two features would not be visible in the model tree.
• Incomplete Objects – Toggles the display of incomplete features.
• Excluded Objects – Toggles the display of excluded components.
• Blanked Objects – Toggles the display of blanked mold/cast components.
• Envelope Components – Toggles the display of envelope components.
• Copied References – Toggles the display of copied references.
Controlling Model Tree Feature Types Display
The display of feature types is a more granular method of determining which level of feature display you wish to use. In the Feature Types section of the Model Tree Items dialog box, you can specifically control which features to display in the model tree:
• Datum Planes
• Datum Axes
• Datum Points
• Coordinate Systems
• Auto Round Members
• Used Sketches — Used sketch features are those external sketches that are used in another feature, such as an Extrude or Revolve feature. When a sketch is used, it is automatically changed to a hidden status, as shown in Figure 4.
Saving Model Tree Display
The model tree display can be saved to a file and loaded at any time. Click Settings from the top of the model tree and select Save Settings File to save the current model tree display. The default save location is the working directory, and the default settings file name is tree.cfg. You can configure Creo Parametric to always consider tree.cfg as the default model tree display.